I want to visualize total contact force result by showing them as a vector plot instead of filled contour, how can I do that?
A python result object can be used to create this rendering:
def post_started(sender, analysis):# Do not edit this line define_dpf_workflow(analysis) def table_retrieve_result(value):# Do not edit this line import mech_dpf import Ans.DataProcessing as dpf wf = dpf.Workflow(this.WorkflowId) wf.Connect('contour_selector', value) this.Evaluate() def define_dpf_workflow(analysis): import mech_dpf import Ans.DataProcessing as dpf mech_dpf.setExtAPI(ExtAPI) filepath = DataModel.AnalysisList[0].ResultFileName #Data sources dataSources = dpf.DataSources(filepath) time_freq_support = dpf.operators.metadata.time_freq_provider() time_freq_support.inputs.data_sources.Connect(dataSources) n_sets = time_freq_support.outputs.time_freq_support.GetData().NumberSets ts = range(1, n_sets + 1) # Get contact data CNF = [] for ids in [43,44,45]: nmisc = dpf.operators.result.nmisc() nmisc.inputs.data_sources.Connect(dataSources) nmisc.Connect(10,ids) nmisc.Connect(11,1) nmisc.inputs.time_scoping.Connect(ts) fc = nmisc.outputs.fields_container.GetData() op = dpf.operators.averaging.elemental_to_nodal_fc() # operator instantiation op.inputs.fields_container.Connect(fc) fcn = op.outputs.fields_container.GetData() CNF.append( fcn ) op = dpf.operators.utility.assemble_scalars_to_vectors_fc() # operator instantiation op.inputs.x.Connect(CNF[0])# optional op.inputs.y.Connect(CNF[1])# optional op.inputs.z.Connect(CNF[2])# optional F_vector = op.outputs.fields_container.GetData() u = dpf.operators.result.displacement() timeScop = dpf.Scoping() timeScop.Ids = ts u.inputs.time_scoping.Connect(timeScop) u.inputs.data_sources.Connect(dataSources) ufc=u.outputs.fields_container.GetData() F_vector.TimeFreqSupport = ufc.TimeFreqSupport output = dpf.operators.utility.forward() output.inputs.any.Connect(F_vector) dpf_workflow = dpf.Workflow() dpf_workflow.Add(u) dpf_workflow.Add(output) dpf_workflow.SetOutputWarpField(u) dpf_workflow.SetOutputContour(output) dpf_workflow.Record('wf_id', False) this.WorkflowId = dpf_workflow.GetRecordedId()
This python result can generate the following rendering:
Hi Jimmy,
thank you for posting the script. It is clear and educative. Could you please verify the operator dpf.operators.averaging.elemental_to_nodal_fc() is working as expected in the code? I have modified your script for my purposes and after extrapolation of contact forces to nodes by the operator, the total contact reaction force changes.
dpf
.
operators
averaging
elemental_to_nodal_fc()
import mech_dpf import Ans.DataProcessing as dpf first_solution = ExtAPI.DataModel.Project.Model.Analyses[0].Solution solver_data = first_solution.SolverData contact_object = ExtAPI.DataModel.GetObjectsByName('test_contact')[0] contact_object_data = solver_data.GetObjectData(contact_object) cont_elem_type_id = contact_object_data.SourceId cont_elems = solver_data.ElementIdsByMaterialId(str(cont_elem_type_id)) cont_nodes = solver_data.NodeIdsByMaterialId(str(cont_elem_type_id)) # result data analysis1 = ExtAPI.DataModel.Project.Model.Analyses[0] dataSource = dpf.DataSources(analysis1.Solution.ResultFilePath) # model my_model = dpf.Model(dataSource) # my mesh op = dpf.operators.mesh.mesh_provider() op.inputs.data_sources.Connect(dataSource) dpf_mesh = op.outputs.mesh.GetData() sub_mesh_scoping = dpf.MeshScopingFactory.ElementalScoping(cont_elems) op = dpf.operators.mesh.mesh_extraction() op.inputs.mesh.Connect(dpf_mesh) op.inputs.mesh_scoping.Connect(sub_mesh_scoping) my_mesh = op.outputs.meshed_region.GetData() # time scoping my_time_scoping = [1] # scoping my_scoping = dpf.Scoping() my_scoping.Location = "Elemental" my_scoping.Ids = cont_elems # NMISC op = dpf.operators.result.nmisc() op.inputs.time_scoping.Connect(my_time_scoping) op.inputs.data_sources.Connect(dataSource) op.inputs.mesh_scoping.Connect(my_scoping) op.inputs.mesh.Connect(my_mesh) op.inputs.item_index.Connect(43) cfx = op.outputs.fields_container.GetData()[0] cfx.Unit = 'N' op = dpf.operators.result.nmisc() op.inputs.time_scoping.Connect(my_time_scoping) op.inputs.data_sources.Connect(dataSource) op.inputs.mesh_scoping.Connect(my_scoping) op.inputs.mesh.Connect(my_mesh) op.inputs.item_index.Connect(44) cfy = op.outputs.fields_container.GetData()[0] cfy.Unit = 'N' op = dpf.operators.result.nmisc() op.inputs.time_scoping.Connect(my_time_scoping) op.inputs.data_sources.Connect(dataSource) op.inputs.mesh_scoping.Connect(my_scoping) op.inputs.mesh.Connect(my_mesh) op.inputs.item_index.Connect(45) cfz = op.outputs.fields_container.GetData()[0] cfz.Unit = 'N' # sum contact force elements cr = [-sum(cfx.Data),-sum(cfy.Data),-sum(cfz.Data)] print(cr) # convert to vectors op = dpf.operators.utility.assemble_scalars_to_vectors() op.inputs.x.Connect(cfx) op.inputs.y.Connect(cfy) op.inputs.z.Connect(cfz) cf = op.outputs.field.GetData() # sum contact force elements sum_cf_op = dpf.operators.math.accumulate() sum_cf_op.inputs.fieldA.Connect(cf) cf_sum = sum_cf_op.outputs.field.GetData() print([-i for i in cf_sum.Data]) # extrapolate to nodes op = dpf.operators.averaging.elemental_to_nodal() op.inputs.field.Connect(cf) cfn = op.outputs.field.GetData() # sum contact force nodes sum_cfn_op = dpf.operators.math.accumulate() sum_cfn_op.inputs.fieldA.Connect(cfn) cfn_sum = sum_cfn_op.outputs.field.GetData() print([-i for i in cfn_sum.Data]) # release rocked rst my_model.ReleaseStreams()
The output I get:
Or don't I see anything trivial?